
You will begin the sliding mesh calculation by initializing the solution (as described in Section 25.14.1) and then specifying the time step size and number of time steps in the Iterate panel, as for any other unsteady calculation. (See Section 25.17 for details about timedependent solutions. Note that if you wish to save the time step size in the initial case file, you can click Apply instead of Iterate and then save a case file before starting to iterate.) FLUENT will iterate on the current time step solution until satisfactory residual reduction is achieved, or the maximum number of iterations per time step is reached. When it advances to the next time step, the cell and wall zones will automatically be moved according to the specified translational or rotational velocities (set in step 2b above). The new interfacezone intersections will be computed automatically, and resultant interior/periodic/external boundary zones will be updated (as described in Section 11.2.2).
Saving Case and Data Files
FLUENT's automatic saving of case and data files (see Section 4.3.4) can be used with the sliding mesh model. This provides a convenient way for you to save results at successive time steps for later postprocessing.

You must save a case file each time you save a data file because the grid position is stored in the case file. Since the grid position changes with each time step, reading data for a given time step will require the case file at that time step so that the grid will be in the proper position. You should also save your initial case file so that you can easily return to the grid's original position to restart the solution if desired.

TimePeriodic Solutions
For some problems (e.g., rotorstator interactions), you may be interested in a timeperiodic solution. That is, the startup transient behavior may not be of interest to you. Once this startup phase has passed, the flow will start to exhibit timeperiodic behavior. If is the period of unsteadiness, then for some flow property at a given point in the flow field:
(11.51) 
For rotating problems, the period (in seconds) can be calculated by dividing the sector angle of the domain (in radians) by the rotor speed (in radians/sec): . For 2D rotorstator problems, , where is the pitch and is the blade speed. The number of time steps in a period can be determined by dividing the time period by the time step size. When the solution field does not change from one period to the next (for example, if the change is less than 5%), a timeperiodic solution has been reached.
To determine how the solution changes from one period to the next, you will need to compare the solution at some point in the flow field over two periods. For example, if the time period is 10 seconds, you can compare the solution at a given point after 22 seconds with the solution after 32 seconds to see if a timeperiodic solution has been reached. If not, you can continue the calculation for another period and compare the solutions after 32 and 42 seconds, and so on until you see little or no change from one period to the next. You can also track global quantities, such as lift and drag coefficients and mass flow, in the same manner. Figure 11.5.1 shows a lift coefficient plot for a timeperiodic solution.
The final timeperiodic solution is independent of the time steps taken during the initial stages of the solution procedure. You can therefore define "large'' time steps in the initial stages of the calculation, since you are not interested in a timeaccurate solution for the startup phase of the flow. Starting out with large time steps will allow the solution to become timeperiodic more quickly. As the solution becomes timeperiodic, however, you should reduce the time step in order to achieve a timeaccurate result.