[Fluent Inc. Logo] return to home search
next up previous contents index

7.17.1 Inputs for Fluid Zones

You will set all fluid conditions in the Fluid panel (Figure  7.17.1), which is opened from the Boundary Conditions panel (as described in Section  7.1.4).

Figure 7.17.1: The Fluid Panel
figure



Defining the Fluid Material


To define the material contained in the fluid zone, select the appropriate item in the Material Name drop-down list. This list will contain all fluid materials that have been defined (or loaded from the materials database) in the Materials panel. If you want to check or modify the properties of the selected material, you can click Edit... to open the Material panel; this panel contains just the properties of the selected material, not the full contents of the standard Materials panel.

figure   

If you are modeling species transport or multiphase flow, the Material Name list will not appear in the Fluid panel. For species calculations, the mixture material for all fluid zones will be the material you specified in the Species Model panel. For multiphase flows, the materials are specified when you define the phases, as described in Section  23.10.3.



Defining Sources


If you wish to define a source of heat, mass, momentum, turbulence, species, or other scalar quantity within the fluid zone, you can do so by enabling the Source Terms option. See Section  7.28 for details.



Defining Fixed Values


If you wish to fix the value of one or more variables in the fluid zone, rather than computing them during the calculation, you can do so by enabling the Fixed Values option. See Section  7.27 for details.



Specifying a Laminar Zone


When you are calculating a turbulent flow, it is possible to "turn off'' turbulence modeling in a specific fluid zone. To disable turbulence modeling, turn on the Laminar Zone option in the Fluid panel. This will disable the turbulence production, but transport the turbulence quantities. If, in addition, you want to set the turbulent viscosity to zero you can do that using the text command define/ boundary-conditions/fluid. You will be asked if you want to Set Turbulent Viscosity to zero within laminar zone?. If your response is yes, FLUENT will set both the production term in the turbulence transport equation and $\mu_t$ to zero. This is useful if you know that the flow in a certain region is laminar. For example, if you know the location of the transition point on an airfoil, you can create a laminar/turbulent transition boundary where the laminar cell zone borders the turbulent cell zone. This feature allows you to model turbulent transition on the airfoil.

Disabling turbulence modeling in a fluid zone, can be applied to all the turbulence models except the Large Eddy Simulation (LES) model.



Specifying a Reaction Mechanism


If you are modeling species transport with reactions, you can enable a reaction mechanism in a fluid zone by turning on the Reaction option and selecting an available mechanism from the Reaction Mechanisms drop-down list. See Section  14.1.4 more information about defining reaction mechanisms.



Specifying the Rotation Axis


If there are rotationally periodic boundaries adjacent to the fluid zone or if the zone is rotating, you must specify the rotation axis. To define the axis, set the Rotation-Axis Direction and Rotation-Axis Origin. This axis is independent of the axis of rotation used by any adjacent wall zones or any other cell zones. For 3D problems, the axis of rotation is the vector from the Rotation-Axis Origin in the direction of the vector given by your Rotation-Axis Direction inputs. For 2D non-axisymmetric problems, you will specify only the Rotation-Axis Origin; the axis of rotation is the $z$-direction vector passing through the specified point. (The $z$ direction is normal to the plane of your geometry so that rotation occurs in the plane.) For 2D axisymmetric problems, you will not define the axis: the rotation will always be about the $x$ axis, with the origin at (0,0).



Defining Zone Motion


To define zone motion for a rotating or translating reference frame, select Moving Reference Frame in the Motion Type drop-down list (visible if you scroll down using the scroll bar to the right of the Rotation-Axis Origin and Direction) and then set the appropriate parameters in the expanded portion of the panel.

To define zone motion for a sliding mesh, select Moving Mesh in the Motion Type drop-down list and then set the appropriate parameters in the expanded portion of the panel. See Section  11.2 for details.

For problems that include linear, translational motion of the fluid zone, specify the Translational Velocity by setting the X, Y, and Z components. For problems that include rotational motion, specify the rotational Speed under Rotational Velocity. The rotation axis is defined as described above.

See Chapter  10 for details about modeling flows in moving reference frames.



Defining Radiation Parameters


If you are using the DO radiation model, you can specify whether or not the fluid zone participates in radiation using the Participates in Radiation option. See Section  13.3.15 for details.


next up previous contents index Previous: 7.17 Fluid Conditions
Up: 7.17 Fluid Conditions
Next: 7.18 Solid Conditions
© Fluent Inc. 2006-09-20