You will enter the following information for a velocity inlet boundary:
All values are entered in the Velocity Inlet panel (Figure 7.4.1), which is opened from the Boundary Conditions panel (as described in Section 7.1.4).
Defining the Velocity
You can define the inflow velocity by specifying the velocity magnitude and direction, the velocity components, or the velocity magnitude normal to the boundary. If the cell zone adjacent to the velocity inlet is moving (i.e., if you are using a rotating reference frame, multiple reference frames, or sliding meshes), you can specify either relative or absolute velocities. For axisymmetric problems with swirl in FLUENT, you will also specify the swirl velocity.
The procedure for defining the inflow velocity is as follows:
Setting the Velocity Magnitude and Direction
If you selected Magnitude and Direction as the Velocity Specification Method in step 1 above, you will enter the magnitude of the velocity vector at the inflow boundary (the Velocity Magnitude) and the direction of the vector:
Figure 7.3.2 shows the vector components for these different coordinate systems.
Setting the Velocity Magnitude Normal to the Boundary
If you selected Magnitude, Normal to Boundary as the Velocity Specification Method in step 1 above, you will enter the magnitude of the velocity vector at the inflow boundary (the Velocity Magnitude). If you are modeling 2D axisymmetric swirl, you will also enter the Tangential-Component of Flow Direction.
Setting the Velocity Components
If you selected Components as the Velocity Specification Method in step 1 above, you will enter the components of the velocity vector at the inflow boundary as follows:
| Remember that positive values for
velocities indicate flow in the positive
directions. If flow enters the domain in the negative
direction, for example, you will need to specify a negative value for the
velocity. The same holds true for the radial, tangential, and axial velocities. Positive radial velocities point radially out from the axis, positive axial velocities are in the direction of the axis vector, and positive tangential velocities are based on the right-hand rule using the positive axis.
Setting the Angular Velocity
If you chose Components as the Velocity Specification Method in step 1 above, and you are modeling axisymmetric swirl, you can specify the inlet Swirl Angular Velocity in addition to the Swirl-Velocity. Similarly, if you chose Components as the Velocity Specification Method and you chose in step 3 to use a Cylindrical or Local Cylindrical coordinate system, you can specify the inlet Angular Velocity in addition to the Tangential-Velocity.
If you specify , is computed for each cell as , where is the radial coordinate in the coordinate system defined by the rotation axis and origin. If you specify both the Swirl-Velocity and the Swirl Angular Velocity, or the Tangential-Velocity and the Angular Velocity, FLUENT will add and to get the swirl or tangential velocity at each cell.
Defining the Temperature
For calculations in which the energy equation is being solved, you will set the static temperature of the flow at the velocity inlet boundary in the Temperature field.
Defining Outflow Gauge Pressure
If you are using one of the density-based solvers, you can specify an Outflow Gauge Pressure for a velocity inlet boundary. If the flow exits the domain at any face on the boundary, that face will be treated as a pressure outlet with the pressure prescribed in the Outflow Gauge Pressure field.
Defining Turbulence Parameters
For turbulent calculations, there are several ways in which you can define the turbulence parameters. Instructions for deciding which method to use and determining appropriate values for these inputs are provided in Section 7.2.2. Turbulence modeling in general is described in Chapter 12.
Defining Radiation Parameters
If you are using the P-1 radiation model, the DTRM, the DO model, or the surface-to-surface model, you will set the Internal Emissivity and (optionally) Black Body Temperature. See Section 13.3.15 for details. (The Rosseland radiation model does not require any boundary condition inputs.)
Defining Species Mass Fractions
If you are modeling species transport, you will set the species mass fractions under Species Mass Fractions. For details, see Section 14.1.5.
Defining Non-Premixed Combustion Parameters
If you are using the non-premixed or partially premixed combustion model, you will set the Mean Mixture Fraction and Mixture Fraction Variance (and the Secondary Mean Mixture Fraction and Secondary Mixture Fraction Variance, if you are using two mixture fractions), as described in Section 15.13.
Defining Premixed Combustion Boundary Conditions
If you are using the premixed or partially premixed combustion model, you will set the Progress Variable, as described in Section 16.3.5.
Defining Discrete Phase Boundary Conditions
If you are modeling a discrete phase of particles, you can set the fate of particle trajectories at the velocity inlet. See Section 22.13 for details.
Defining Multiphase Boundary Conditions
If you are using the VOF, mixture, or Eulerian model for multiphase flow, you will need to specify volume fractions for secondary phases and (for some models) additional parameters. See Section 23.9.8 for details.