[Fluent Inc. Logo] return to home search
next up previous contents

10. solve/

animate/
Enter the animation menu.

define/
Enter the animation definition menu.

define-monitor
Define new animation.

edit-monitor
Change animation monitor attributes.

playback/
Enter the animation playback menu.

delete
Delete animation sequence.

play
Play the selected animation.

read
Read new animation from file or already-defined animations.

write
Write animation sequence to the file.

dpm-update
Update discrete phase source terms.

dual-time-iterate
Perform unsteady iterations for a specified number of time steps.

execute-commands/
Enter the execute commands menu.

add-edit
Add or edit execute commands.

disable
Disable an execute command.

enable
Enable an execute command.

initialize/
Enter the flow initialization menu.

compute-defaults/
Enter the compute default values menu. You can select the type of zone from which you want to compute these values.

dpm-reset
Reset discrete phase source terms to zero.

fmg-initialization
Initialize using the full-multigrid initialization (FMG).

init-flow-statistics
Initialize unsteady statistics.

initialize-flow
Initialize the flow field with the current default values.

init-instantaneous-vel
Initialize unsteady velocity.

list-defaults
List default values.

repair-wall-distance
Correct wall distance at very high aspect ratio hexahedral/polyhedral cells.

set-defaults/
Set default initial values.

set-fmg-initialization/
Enter the set full-multigrid for initialization menu. Initial values for each variable can be set within this menu.

iterate
Perform a specified number of iterations.

mesh-motion
Perform mesh motion.

monitors/
Set solution monitors.

force/
Enter the force monitors menu.

clear-all-monitors-data
Discard the internal and external file data associated with the force monitors.

clear-drag-monitor-data
Discard the internal and external file data (if any exist) for the drag coefficient.

clear-lift-monitor-data
Discard the internal and external file data (if any exist) for the lift coefficient.

clear-moment-monitor-data
Discard the internal and external file data (if any exist) for the moment coefficient.

drag-coefficient
Set the parameters for monitoring the drag coefficient, including the list of wall zones on which to compute the coefficient, whether to print, plot, and/or write the data, the name of the output file (if appropriate), the plot window, and the force vector associated with the coefficient.

lift-coefficient
Set the parameters for monitoring the lift coefficient, including the list of wall zones on which to compute the coefficient, whether to print, plot, and/or write the data, the name of the output file (if appropriate), the plot window, and the force vector associated with the coefficient.

moment-coefficient
Set the parameters for monitoring the moment coefficient, including the list of wall zones on which to compute the coefficient, whether to print, plot, and/or write the data, the name of the output file (if appropriate), the plot window, the moment center associated with the coefficient, and which component of the moment vector to monitor.

monitor-unsteady-iters?
Specify (for transient calculations) whether the monitors are updated every iteration or every time step.

residual/
Enter the residual monitors menu.

check-convergence?
Choose which currently-monitored residuals should be checked for convergence.

convergence-criteria
Set convergence criteria for residuals that are currently being both monitored and checked.

criterion-type
Set convergence criterion type.

monitor?
Choose which residuals to monitor as printed and/or plotted output.

n-display
Set the number of most recent residuals to display in plots.

n-maximize-norms
Set the number of iterations through which normalization factors will be maximized.

normalization-factors
Set normalization factors for currently-monitored residuals (if normalize? is set to yes).

normalize?
Choose whether to normalize residuals in printed and plotted output.

n-save
Set number of residuals to be saved with data. History is automatically compacted when buffer becomes full.

plot?
Choose whether residuals will be plotted during iteration.

print?
Choose whether residuals will be printed during iteration.

relative-conv-criteria
Set relative convergence criteria for residuals that are currently being both monitored and checked.

re-normalize
Re-normalize residuals by maximum values.

reset?
Choose whether to delete the residual history and reset iteration counter to 1.

scale-by-coefficient?
Choose whether to scale residuals by coefficient sum in printed and plotted output.

window
Specify window in which residuals will be plotted during iteration.

statistic/
Enter the statistic monitors menu.

monitors
Choose which statistics to monitor as printed and/or plotted output.

plot?
Choose whether or not statistics will be plotted during iteration.

print?
Choose whether or not statistics will be printed during iteration.

window
Specify first window in which statistics will be plotted during iteration. Multiple statistics are plotted in separate windows, beginning with this one.

surface/
Contains commands to control surface monitoring.

clear-data
Clear current surface monitor data.

clear-monitors
Remove all defined surface monitors.

curves/
Enter the curves menu.

lines
Set lines parameters for surface monitors.

markers
Set markers parameters for surface monitors.

list-monitors
List defined surface monitors.

set-monitor
Define or modify a surface monitor.

volume/
Contains commands to control volume monitoring.

clear-data
Clear current volume monitor data.

clear-monitors
Remove all defined volume monitors.

list-monitors
List defined volume monitors.

set-monitor
Define or modify a volume monitor.

particle-history/
Enter the particle-history menu.

export-particle-data
Export particle history data.

import-particle-data
Import particle history data.

patch
Patch a value for a flow variable in the domain.

set/
Enter the set solution parameters menu.

adaptive-time-stepping
Set adaptive time stepping parameters.

bc-pressure-extrapolations
Set pressure extrapolations schemes on boundaries.

correction-tolerance/
Enter the correction tolerance menu.

courant-number
Set the fine-grid Courant number (time step factor). This command is available only for the coupled solvers.

data-sampling
Enable data sampling for unsteady flow statistics.

disable-reconstruction?
Completely disables reconstruction, resulting in totally first-order accuracy.

discretization-scheme/
Enter the discretization scheem menu. This allows you to select the discretization scheme for the convection terms in the solution equations, as well as the pressure-velocity coupling scheme for the pressure-based solver.

pressure
Select which Pressure model is to be used. Five models are available:


Index Model
10 Standard
11 Linear
12 Second Order
13 Body Force Weighted
14 PRESTO!

flow
Select which Pressure-Velocity Coupling model is to be used. Three models are available:


Index Model
20 SIMPLE
21 SIMPLEC
22 PISO

mom
Select which Momentum model is to be used. Four models are available:


Index Model
0 First Order Upwind
1 Second Order Upwind
2 Power Law
4 QUICK

The Energy and Turbulence models are indexed as in the Momentum model table above.

Contact your Fluent technical support engineer for more details.

equations/
Select the equations to be solved.

expert
Set expert options.

flow-warnings?
Specify whether or not to print warning messages when reversed flow occurs at inlets and outlets, and when mass flow inlets develop supersonic regions. By default, flow warnings are printed.

flux-type
Set the flux type.

gradient-scheme
Set gradient options.

limiter-warnings?
Specify whether or not to print warning messages when quantities are being limited. By default, limiter warnings are printed.

limits
Set solver limits for various solution variables, in order to improve the stability of the solution.

max-corrections/
Enter the set max-corrections menu.

multi-grid-amg
Set the parameters that govern the algebraic multigrid procedure.

multi-grid-controls/
Set multigrid parameters and termination criteria.

multi-grid-fas
Set the parameters that control the FAS multigrid solver. This command appears only when the explicit coupled solver is used.

multi-stage
Set the multi-stage coefficients and the dissipation and viscous evaluation stages. This command appears only when the explicit coupled solver is used.

numerics
Set numerics options.

predict-next-time?
Applies a predictor algorithm for computing.

p-v-controls
Set pressure-velocity controls.

p-v-coupling
Select the pressure-velocity coupling scheme.

reactions?
Enable the species reaction sources and set relaxation factor.

relaxation-factor/
Enter the relaxation-factor menu.

relaxation-method
Set the solver relaxation method.

reporting-interval
Set the number of iterations for which convergence monitors are reported. The default is 1 (after every iteration).

residual-smoothing
Set the implicit residual smoothing parameters. This command is available only for the explicit coupled solver.

residual-tolerance/
Enter the residual tolerance menu.

residual-verbosity
Set the amount of residual information to be printed. A value of 0 (the default) prints residuals at the end of each fine grid iteration. A value of 1 prints residuals after every stage of the fine grid iteration. A value of 2 prints residuals after every stage on every grid level.

set-controls-to-default
Set controls to default values.

slope-limiter-set/
Select a new Fluent solver slope limiter.

stiff-chemistry
Set solver options for stiff chemistry solutions.

surface-tension
Set surface-tension calculation options.

time-step
Set the magnitude of the (physical) time step $\Delta t$.

under-relaxation/
Enter the under-relaxation menu, which allows you to set the under-relaxation factor for each equation that is being solved in a segregated manner.

variable-time-stepping
Set variable time-stepping options for VOF explicit schemes.

update-physical-time
Advance the unsteady solution to the next physical time level. Using this command in conjunction with the iterate command allows you to manually advance the solution in time (rather than doing it automatically with the dual-time-iterate command).


next up previous contents Previous: 9. report/
Up: FLUENT 6.3 Text Command List
Next: 11. surface/
© Fluent Inc. 2006-10-05