PLESOL, Item, Comp, KUND, Fact
Displays the solution results as discontinuous element contours.

Label identifying the item. Valid item labels are shown in Table: PLESOL - Valid Item and Component Labels below. Some items also require a component label.


Component of the item (if required). Valid component labels are shown in Table: PLESOL - Valid Item and Component Labels below.


Undisplaced shape key:

0 — 

Do not overlay undeformed structure display

1 — 

Overlay displaced contour plot with undeformed display (appearance is system-dependent)

2 — 

Overlay displaced contour plot with undeformed edge display (appearance is system-dependent)


Scale factor for 2-D display of contact items (defaults to 1). A negative scaling factor may be used to invert the display.


Displays the solution results as element contours discontinuous across element boundaries for the selected elements. For example, PLESOL,S,X displays the X component of stress S (that is, the SX stress component). Various element results depend on the calculation method and the selected results location (AVPRIN, RSYS, and ESEL). Contours are determined by linear interpolation within each element, unaffected by the surrounding elements (i.e., no nodal averaging is performed). The discontinuity between contours of adjacent elements is an indication of the gradient across elements. Component results are displayed in the active results coordinate system [RSYS] (default is the global Cartesian). See the ETABLE and PLETAB commands for displaying items not available through this command (such as line element results).

For PowerGraphics displays [/GRAPHICS,POWER], results are plotted only for the model exterior surface. The items marked with [1] in Table: PLESOL - Valid Item and Component Labels are not supported by PowerGraphics.

Table: PLESOL - Valid Item and Component Labels

General Item and Component Labels PLESOL, Lab, Item, Comp
Valid item and component labels for element results are:
SX, Y, Z, XY, YZ, XZComponent stress.
1, 2, 3Principal stress.
INTStress intensity.
EQVEquivalent stress.
EPELX, Y, Z, XY, YZ, XZComponent elastic strain.
1, 2, 3Principal elastic strain.
INTElastic strain intensity.
EQVElastic equivalent strain.
EPPLX, Y, Z, XY, YZ, XZComponent plastic strain.
1, 2, 3Principal plastic strain.
INTPlastic strain intensity.
EQVPlastic equivalent strain.
EPCRX, Y, Z, XY, YZ, XZComponent creep strain.
1, 2, 3Principal creep strain.
INTCreep strain intensity.
EQVCreep equivalent strain.
EPTHX, Y, Z, XY, YZ, XZComponent thermal strain.
1, 2, 3Principal thermal strain.
INTThermal strain intensity.
EQVThermal equivalent strain.
EPSW Swelling strain.
EPTO X, Y, Z, XY, YZ, XZComponent total mechanical strain (EPEL + EPPL + EPCR).
1, 2, 3Principal total mechanical strain.
INTTotal mechanical strain intensity.
EQVTotal mechanical equivalent strain.
EPTTX, Y, Z, XY, YZ, XZTotal mechanical and thermal strain (EPEL + EPPL + EPCR + EPTH). [8]
1, 2, 3Principal total mechanical and thermal strain.
INTTotal mechanical and thermal strain intensity.
EQVTotal mechanical and thermal equivalent strain.
EPDIX, Y, Z, XY, YZ, XZComponent diffusion strain [1]
 1, 2, 3Principal diffusion strain
 INTDiffusion strain intensity
 EQVDiffusion equivalent strain
NLSEPLEquivalent stress (from stress-strain curve).
SRATStress state ratio.
HPRESHydrostatic pressure.
EPEQAccumulated equivalent plastic strain.
CREQAccumulated equivalent creep strain.
PSVPlastic state variable.
PLWKPlastic work/volume.
SENDELASTICElastic strain energy density.
PLASTICPlastic strain energy density.
CREEPCreep strain energy density.
CDMDMGDamage variable
LMMaximum previous strain energy for virgin material
FAILMAXMaximum of all active failure criteria defined at the current location (See the FCTYP command for details.) [1][3]
EMAXMaximum Strain Failure Criterion. [1][3]
SMAXMaximum Stress Failure Criterion. [1][3]
TWSITsai-Wu Strength Index Failure Criterion. [1][3]
TWSRInverse of Tsai-Wu Strength Ratio Index Failure Criterion. [1][3]
HFIBHashin Fiber Failure Criterion. [1][3][5]
HMATHashin Matrix Failure Criterion. [1][3][5]
PFIBPuck Fiber Failure Criterion. [1][3][5]
PMATPuck Matrix Failure Criterion. [1][3][5]
L3FBLaRc03 Fiber Failure Criterion. [1][3][5]
L3MTLaRc03 Matrix Failure Criterion. [1][3][5]
L4FBLaRc04 Fiber Failure Criterion. [1][3][5]
L4MTLaRc04 Matrix Failure Criterion. [1][3][5]
USR1, USR2, ..., USR9User-defined failure criteria. [1][3][4][5]

Failure criteria based on the effective stresses in the damaged material.

Components: Maximum of all failure criteria defined at current location (MAX), fiber tensile failure (FT), fiber compressive failure (FC), matrix tensile failure (MT), and matrix compressive (MC).


Progressive damage parameters.

Components: Damage status (STAT, 0--undamaged, 1--damaged), fiber tensile damage variable (FT), fiber compressive damage variable (FC), matrix tensile damage variable (MT), matrix compressive damage variable (MC), shear damage variable (S), and energy dissipated per unit volume (SED).

FCMXLAYLayer number where the maximum of all active failure criteria over the entire element occurs. [1][3]
FCNumber of the maximum-failure criterion over the entire element [1][3] :
1 - EMAX
2 - SMAX
3 - TWSI
4 - TWSR
5 - PFIB
6 - PMAT
7 - HFIB
8 - HMAT
9 - L3FB
10 - L3MT
11 - L4FB
12 - L4MT
13~21 - USR1~USR9
VALValue of the maximum failure criterion over the entire element. [1][3]
SVAR1, 2, 3, ... NState variable. [1]
GKSX, XY, XZGasket component stress.
GKDX, XY, XZGasket component total closure.
GKDIX, XY, XZGasket component total inelastic closure.
GKTHX, XY, XZGasket component thermal closure.
SSX, XY, XZInterface traction (stress)
SDX, XY, XZInterface separation
CONT STATContact status [2]:
3-closed and sticking
2-closed and sliding
1-open but near contact
0-open and not near contact
PENEContact penetration
PRESContact pressure
SFRICContact friction stress
STOTContact total stress (pressure plus friction)
SLIDEContact sliding distance
GAPContact gap distance
FLUXTotal heat flux at contact surface
CNOSTotal number of contact status changes during substep.
FPRSFluid penetration pressure
TGX, Y, Z, SUMComponent thermal gradient or vector sum.
TFX, Y, Z, SUMComponent thermal flux or vector sum.
PGX, Y, Z, SUMComponent pressure gradient or vector sum.
EFX, Y, Z, SUMComponent electric field or vector sum.
DX, Y, Z, SUMComponent electric flux density or vector sum.
HX, Y, Z, SUMComponent magnetic field intensity or vector sum.
BX, Y, Z, SUMComponent magnetic flux density or vector sum.
CGX, Y, Z, SUMComponent concentration gradient or vector sum [1]
DFX, Y, Z, SUMComponent diffusion flux density or vector sum [1]
FMAGX, Y, Z, SUMComponent electromagnetic force or vector sum [1].
PX, Y, Z, SUMPointing vector component or sum [1].
SERR[6] Structural error energy [1].
SDSG[6] Absolute value of the maximum variation of any nodal stress component [1].
TERR[6] Thermal error energy [1].
TDSG[6] Absolute value of the maximum variation of any nodal thermal gradient component [1].
FX, Y, ZX, Y, or Z structural force [1][7].
MX, Y, ZX, Y, or Z structural moment [1].
HEAT Heat flow [1].
FLOW Fluid flow [1].
AMPS Current flow [1]. Use FORCE for type.
CHRG Charge [1]. Use FORCE for type.
FLUX Magnetic flux [1].
CSGX, Y, ZX, Y, or Z magnetic current segment component [1].
RATE Diffusion flow rate
SENE "Stiffness" energy or thermal heat dissipation. Same as TENE [1].
STEN Elemental energy dissipation due to stabilization [1].
TENE Thermal heat dissipation or "stiffness" energy. Same as SENE [1].
KENE Kinetic energy [1].
AENE Artificial energy due to hourglass control/drill stiffness or due to contact stabilization [1].
JHEAT Element Joule heat generation [1].
JSX, Y, Z, SUMSource current density for low-frequency magnetic analyses. Total current density (sum of conduction and displacement current densities) in low frequency electric analyses. Components (X, Y, Z) and vector sum (SUM). [1].
JTX, Y, Z, SUMTotal measureable current density in low-frequency electromagnetic analyses. (Conduction current density in a low-frequency electric analysis.) Components (X, Y, Z) and vector sum (SUM). [1].
JCX, Y, Z, SUMConduction current density for elements that support conduction current calculation. Components (X, Y, Z) and vector sum (SUM). [1].
MRE Magnetic Reynolds number [1].
VOLU Volume of volume element [1].
CENTX, Y, ZCentroid X, Y, or Z location (based on shape function) in the active coordinate system [1].
BFETEMPBody temperatures (calculated from applied temperatures) as used in solution (area and volume elements only).
SMISCsnumElement summable miscellaneous data value at sequence number snum (shown in the Output Data section of each element description found in the Element Reference).
NMISCsnumElement non-summable miscellaneous data value at sequence number snum (shown in the Output Data section of each element description found in the Element Reference).
CAPC0,X0,K0,ZONE, DPLS,VPLSMaterial cap plasticity model only: Cohesion; hydrostatic compaction yielding stress; I1 at the transition point at which the shear and compaction envelopes intersect; zone = 0: elastic state, zone = 1: compaction zone, zone = 2: shear zone, zone = 3: expansion zone; effective deviatoric plastic strain; volume plastic strain.
EDPCCSIG,CSTRMaterial EDP creep model only (not including the cap model): Equivalent creep stress; equivalent creep strain.
FICTTEMPFictive temperature.
ESIGX,Y,Z,XY,YZ,ZXComponents of Biot’s effective stress.
1, 2, 3Principal stresses of Biot’s effective stress.
INTStress intensity of Biot’s effective stress.
EQVEquivalent stress of Biot’s effective stress.
DPAR TPORTotal porosity (Gurson material model).
GPORPorosity due to void growth.
NPORPorosity due to void nucleation.
FFLXX,Y,ZFluid flow flux in poromechanics.
  1. Not supported by PowerGraphics

  2. For MPC-based contact definitions, the value of STAT can be negative. This indicates that one or more contact constraints were intentionally removed to prevent overconstraint. STAT = -3 is used for MPC bonded contact; STAT = -2 is used for MPC no-separation contact.

  3. Works only if failure criteria information is provided. (For more information, see the documentation for the FC and TB commands.)

  4. Works only if user-defined failure criteria routine is provided.

  5. Must be added via the FCTYP command first.

  6. Some element- and material-type limitations apply. (For more information, see the documentation for the PRERR command.)

  7. Do not use the PLESOL command to obtain contact forces for contact elements. The force values reported by this command may not be accurate for these elements. Instead, use the ETABLE command to obtain contact force values.

  8. Total mechanical, thermal, and ddiffusion strain (EPEL + EPPL + EPCR + EPTH + EPDI) in coupled-diffusion analyses.

Menu Paths

Main Menu>General Postproc>Plot Results>Contour Plot>Element Solu
Utility Menu>Plot>Results>Contour Plot>Elem Solution

Release 14.0 - © 2011 SAS IP, Inc. All rights reserved.