**PRESOL**, * Item*,

`Comp`

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | DYNA

`Item`

Label identifying the item. Valid item labels are shown in

*Table 213: PRESOL - Valid Item and Component Labels for Element Results*below. Some items also require a component label.`Comp`

Component of the item (if required). Valid component labels are shown in

*Table 213: PRESOL - Valid Item and Component Labels for Element Results*below.

Prints the solution results for the selected elements in the
sorted sequence. For example, **PRESOL**,S prints
the stress items SX, SY, SZ, SXY, SYZ, and SXZ for the node locations
of the element. Component results are in the global Cartesian coordinate
directions unless transformed (**RSYS**).

Shell elements print values at the top, then bottom of the element (or layer). If KEYOPT(8) = 2 (for SHELL181, SHELL208, SHELL209, SHELL281, or ELBOW290), the results are printed in the order TOP, BOT and then MID of each element, (or layer). The MID value will be the actual value as written to the results file.

Items are listed as columns of a table versus element number. An exception occurs for item ELEM which uses an element format (all applicable line element results are listed per element) instead of a tabular format.

The **FORCE** command can be used to define which
component of the nodal load is to be used (static, damping, inertia,
or total). See the **ETABLE** and **PRETAB** commands for printing items not available through this command (such
as line element results).

For PowerGraphics [**/GRAPHICS**,POWER], results
are listed only for the element surface. The items marked with [*1*] are not supported by PowerGraphics.

**Table 213: PRESOL - Valid Item and Component Labels for Element Results**

General
Item and Component Labels PRESOL, `Item, Comp` | ||
---|---|---|

Item | Comp | Description |

S | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) stresses. |

PRIN | Principal stresses (1, 2, 3), stress intensity (INT), and equivalent stress (EQV) | |

EPEL | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) elastic strains. |

PRIN | Principal elastic strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPTH | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) thermal strains. |

PRIN | Principal thermal strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPPL | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) plastic strains. |

PRIN | Principal plastic strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPCR | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) creep strains. |

PRIN | Principal creep strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPSW | Swelling strain. | |

EPTO | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) total mechanical strains (EPEL + EPPL + EPCR). |

PRIN | Principal total mechanical strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPTT | COMP or blank | Component
(X, Y, Z, XY, YZ, XZ) total mechanical and thermal strains (EPEL + EPPL + EPCR + EPTH). |

PRIN | Principal total mechanical and thermal strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

EPDI | COMP or blank | Component (X, Y, Z, XY, YZ, XZ) diffusion strains. |

PRIN | Principal diffusion strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV) | |

NL | Nonlinear items (SEPL, SRAT, HPRES, EPEQ, CREQ, PSV, PLWK). | |

SEND | ELASTIC | Elastic strain energy density. |

PLASTIC | Plastic strain energy density. | |

CREEP | Creep strain energy density. | |

DAMAGE | Damage strain energy density. | |

VDAM | Viscoelastic dissipation energy density. | |

VREG | Visco-regularization strain energy density. | |

ENTO | Total strain energy density. | |

CDM | DMG | Damage variable. |

LM | Maximum previous strain energy for virgin material. | |

FAIL | Failure criteria for virgin material [
Issue the | |

PFC | Failure criteria based on the effective stresses in the damaged material.
| |

PDMG | Progressive damage parameters.
| |

FCMX | Maximum failure criterion over the entire element [1][2]. Components:
Layer number where the maximum occurs (LAY), name of the maximum failure
criterion (FC), and value of the maximum failure criterion (VAL). | |

SVAR | 1,2,3, ... N | State variable. |

GKS | Gasket component (X, XY, XZ) stress. | |

GKD | Gasket component (X, XY, XZ) total closure. | |

GKDI | Gasket component (X, XY, XZ) total inelastic closure. | |

GKTH | Gasket component (X, XY, XZ) thermal closure. | |

CONT | Contact items (STAT, PENE, PRES, SFRIC, STOT,
SLIDE, GAP, FLUX, CNOS, FPRS). See component descriptions in PLESOL. | |

TG | Component (X, Y, Z) thermal gradients and vector sum (SUM). | |

TF | Component (X, Y, Z) thermal fluxes and vector sum (SUM). | |

PG | Component (X, Y, Z) pressure gradients and vector sum (SUM). | |

EF | Component (X, Y, Z) electric fields and vector sum (SUM). | |

D | Component (X, Y, Z) electric flux densities and vector sum (SUM). | |

H | Component (X, Y, Z) magnetic field intensities and vector sum (SUM). | |

B | Component (X, Y, Z) magnetic flux densities and vector sum (SUM). | |

CG | Component concentration gradient or vector sum | |

DF | Component diffusion flux density or vector sum | |

FMAG | Component
(X, Y, Z) electromagnetic forces and vector sum (SUM) [1]. | |

P | Poynting vector components (X, Y,
Z) and sum (SUM) [1]. | |

CG | Concentration gradient | |

F | Component (X, Y, Z) structural forces. Use FORCE for type [1][5]. | |

M | Component (X, Y, Z) structural moments.
Use FORCE for type [1]. | |

HEAT | Heat flow. Use FORCE for type [1]. | |

FLOW | Fluid flow. Use FORCE for type. | |

AMPS | Current flow [1]. Use FORCE for type. | |

CHRG | Charge [1]. Use FORCE for type. | |

FLUX | Magnetic flux [1]. | |

CSG | Component (X, Y, Z) magnetic current segments. Use FORCE for type [1]. | |

FORC | All
available force items (F to CSG above). (10 maximum) [1]. | |

RATE | Diffusion flow rate | |

BFE | Body temperatures (calculated from applied temperatures) as used in solution (area and volume elements only). | |

ELEM | All applicable element results (available only
for LINK180 and previous-generation structural
line elements) [1]. | |

SERR[3] | Structural error energy [1]. | |

SDSG[3] | Absolute value of the maximum variation of any nodal stress
component [1]. | |

TERR[3] | Thermal error energy [1]. | |

TDSG[3] | Absolute value of the maximum variation of any nodal thermal
gradient component [1]. | |

SENE | "Stiffness"
energy or thermal heat dissipation. Same as TENE [1]. | |

STEN | Elemental energy dissipation due to stabilization. | |

TENE | Thermal heat dissipation or "stiffness" energy. Same as SENE
[1]. | |

KENE | Kinetic energy [1]. | |

AENE | Artificial energy due to hourglass
control/drill stiffness or due to contact stabilization [1]. | |

JHEAT | Element Joule heat generation
(coupled-field calculation) [1]. | |

JS | Source
current density for low-frequency magnetic analyses. Total current
density (sum of conduction and displacement current densities) in
low frequency electric analyses. Components (X, Y, Z) and vector sum
(SUM). [1]. | |

JT | Total measureable
current density in low-frequency electromagnetic analyses. (Conduction
current density in a low-frequency electric analysis.) Components
(X, Y, Z) and vector sum (SUM). [1]. | |

JC | Conduction current
density for elements that support conduction current calculation.
Components (X, Y, Z) and vector sum (SUM). [1]. | |

MRE | Magnetic Reynolds number [1]. | |

VOLU | Volume of volume element [1]. | |

CENT | Centroid X, Y, or Z location (based
on shape function) in the active coordinate system [1]. | |

LOCI | Integration point location | |

SMISC | `snum` | Element summable miscellaneous data value at sequence
number (Shown in the Output
Data section of each element description. See Chapter 4 of the `snum` Element Reference)
[1]. |

NMISC | `snum` | Element nonsummable miscellaneous data value at sequence
number (Shown in the Output
Data section of each element description. See Chapter 4 of the `snum` Element Reference)
[1]. |

CAP | C0,X0,K0,ZONE, DPLS,VPLS | Material cap plasticity model only: Cohesion; hydrostatic compaction yielding stress; I1 at the transition point at which the shear and compaction envelopes intersect; zone = 0: elastic state, zone = 1: compaction zone, zone = 2: shear zone, zone = 3: expansion zone; effective deviatoric plastic strain; volume plastic strain. |

EDPC | CSIG,CSTR | Material EDP creep model only (not including the cap model): equivalent creep stress; equivalent creep strain. |

FICT | TEMP | Fictive temperature. |

ESIG | X,Y,Z,XY,YZ,ZX | Components of Biot’s effective stress. |

1, 2, 3 | Principal stresses of Biot’s effective stress. | |

INT | Stress intensity of Biot’s effective stress. | |

EQV | Equivalent stress of Biot’s effective stress. | |

DPAR | TPOR | Total porosity (Gurson material model). |

GPOR | Porosity due to void growth. | |

NPOR | Porosity due to void nucleation. | |

FFLX | X,Y,Z | Fluid flow flux in poromechanics. |

MENE | Acoustic potential energy [1]. | |

PMSV | VRAT,PPRE | Void volume ratio and pore pressure for coupled pore-pressure CPT elements. |

FPIDX | TF01,SF01, TF02,SF02, TF03,SF03, TF04,SF04 | Failure plane surface activity status for concrete and joint rock material models: 1 for yielded and 0 for not yielded. Tension and shear failure status are available for all four sets of failure planes. |

YSIDX | TENS,SHEA | Yield surface activity status for Mohr-Coloumb, soil, concrete, and joint rock material models: 1 for yielded and 0 for not yielded. |

Works only if failure criteria information is provided. (For more information, see the documentation for the

**FC**and**TB**commands.)Some element- and material-type limitations apply. (For more information, see the documentation for the

**PRERR**command.)Do not use the

**PRESOL**command to obtain contact forces for contact elements. The force values reported by this command may not be accurate for these elements. Instead, use the**ETABLE**command to obtain contact force values.