PRESOL

PRESOL, Item, Comp
Prints the solution results for elements.

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | DYNA

Item

Label identifying the item. Valid item labels are shown in Table 213: PRESOL - Valid Item and Component Labels for Element Results below. Some items also require a component label.

Comp

Component of the item (if required). Valid component labels are shown in Table 213: PRESOL - Valid Item and Component Labels for Element Results below.

Notes

Prints the solution results for the selected elements in the sorted sequence. For example, PRESOL,S prints the stress items SX, SY, SZ, SXY, SYZ, and SXZ for the node locations of the element. Component results are in the global Cartesian coordinate directions unless transformed (RSYS).

Shell elements print values at the top, then bottom of the element (or layer). If KEYOPT(8) = 2 (for SHELL181, SHELL208, SHELL209, SHELL281, or ELBOW290), the results are printed in the order TOP, BOT and then MID of each element, (or layer). The MID value will be the actual value as written to the results file.

Items are listed as columns of a table versus element number. An exception occurs for item ELEM which uses an element format (all applicable line element results are listed per element) instead of a tabular format.

The FORCE command can be used to define which component of the nodal load is to be used (static, damping, inertia, or total). See the ETABLE and PRETAB commands for printing items not available through this command (such as line element results).

For PowerGraphics [/GRAPHICS,POWER], results are listed only for the element surface. The items marked with [1] are not supported by PowerGraphics.

Table 213:  PRESOL - Valid Item and Component Labels for Element Results

General Item and Component Labels PRESOL, Item, Comp
ItemCompDescription
SCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) stresses.
PRINPrincipal stresses (1, 2, 3), stress intensity (INT), and equivalent stress (EQV)
EPELCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) elastic strains.
PRINPrincipal elastic strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPTHCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) thermal strains.
PRINPrincipal thermal strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPPLCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) plastic strains.
PRINPrincipal plastic strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPCRCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) creep strains.
PRINPrincipal creep strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPSW Swelling strain.
EPTOCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) total mechanical strains (EPEL + EPPL + EPCR).
PRINPrincipal total mechanical strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPTTCOMP or blankComponent (X, Y, Z, XY, YZ, XZ) total mechanical and thermal strains (EPEL + EPPL + EPCR + EPTH).
PRINPrincipal total mechanical and thermal strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
EPDICOMP or blankComponent (X, Y, Z, XY, YZ, XZ) diffusion strains.
PRINPrincipal diffusion strains (1, 2, 3), strain intensity (INT), and equivalent strain (EQV)
NL Nonlinear items (SEPL, SRAT, HPRES, EPEQ, CREQ, PSV, PLWK).
SENDELASTICElastic strain energy density.
PLASTICPlastic strain energy density.
CREEPCreep strain energy density.
DAMAGEDamage strain energy density.
VDAMViscoelastic dissipation energy density.
VREGVisco-regularization strain energy density.
ENTOTotal strain energy density.
CDMDMGDamage variable.
LMMaximum previous strain energy for virgin material.
FAIL 

Failure criteria for virgin material [1][2].

Default components: Maximum of all failure criteria defined at current location (MAX), maximum strain (EMAX), maximum stress (SMAX), Tsai-Wu Strength Index (TWSI), inverse of Tsai-Wu Strength Ratio Index (TWSR).

Other available components: Hashin Fiber Failure (HFIB), Hashin Matrix Failure (HMAT), Puck Fiber Failure (PFIB), Puck Matrix Failure (PMAT), LaRc03 Fiber Failure (L3FB), LaRc03 Matrix Failure (L3MT), LaRc04 Fiber Failure (L4FB), LaRc04 Matrix Failure (L4MT), and any user-defined failure criteria (USR1 through USR9) [4].

Issue the FCTYP command to activate or remove failure criteria.

PFC 

Failure criteria based on the effective stresses in the damaged material.

Components: Maximum of all failure criteria defined at current location (MAX), fiber tensile failure (FT), fiber compressive failure (FC), matrix tensile failure (MT), and matrix compressive (MC).

PDMG 

Progressive damage parameters.

Components: Damage status (STAT, 0 - undamaged, 1 - damaged, 2 - complete damage), fiber tensile damage variable (FT), fiber compressive damage variable (FC), matrix tensile damage variable (MT), matrix compressive damage variable (MC), shear damage variable (S), energy dissipated per unit volume (SED), energy per unit volume due to viscous damping (SEDV).

FCMX Maximum failure criterion over the entire element [1][2]. Components: Layer number where the maximum occurs (LAY), name of the maximum failure criterion (FC), and value of the maximum failure criterion (VAL).
SVAR1,2,3, ... NState variable.
GKS Gasket component (X, XY, XZ) stress.
GKD Gasket component (X, XY, XZ) total closure.
GKDI Gasket component (X, XY, XZ) total inelastic closure.
GKTH Gasket component (X, XY, XZ) thermal closure.
CONT Contact items (STAT, PENE, PRES, SFRIC, STOT, SLIDE, GAP, FLUX, CNOS, FPRS). See component descriptions in PLESOL.
TG Component (X, Y, Z) thermal gradients and vector sum (SUM).
TF Component (X, Y, Z) thermal fluxes and vector sum (SUM).
PG Component (X, Y, Z) pressure gradients and vector sum (SUM).
EF Component (X, Y, Z) electric fields and vector sum (SUM).
D Component (X, Y, Z) electric flux densities and vector sum (SUM).
H Component (X, Y, Z) magnetic field intensities and vector sum (SUM).
B Component (X, Y, Z) magnetic flux densities and vector sum (SUM).
CG Component concentration gradient or vector sum
DF Component diffusion flux density or vector sum
FMAG Component (X, Y, Z) electromagnetic forces and vector sum (SUM) [1].
P Poynting vector components (X, Y, Z) and sum (SUM) [1].
CG Concentration gradient
F Component (X, Y, Z) structural forces. Use FORCE for type [1][5].
M Component (X, Y, Z) structural moments. Use FORCE for type [1].
HEAT Heat flow. Use FORCE for type [1].
FLOW Fluid flow. Use FORCE for type.
AMPS Current flow [1]. Use FORCE for type.
CHRG Charge [1]. Use FORCE for type.
FLUX Magnetic flux [1].
CSG Component (X, Y, Z) magnetic current segments. Use FORCE for type [1].
FORC All available force items (F to CSG above). (10 maximum) [1].
RATE Diffusion flow rate
BFE Body temperatures (calculated from applied temperatures) as used in solution (area and volume elements only).
ELEM All applicable element results (available only for LINK180 and previous-generation structural line elements) [1].
SERR[3] Structural error energy [1].
SDSG[3] Absolute value of the maximum variation of any nodal stress component [1].
TERR[3] Thermal error energy [1].
TDSG[3] Absolute value of the maximum variation of any nodal thermal gradient component [1].
SENE "Stiffness" energy or thermal heat dissipation. Same as TENE [1].
STEN Elemental energy dissipation due to stabilization.
TENE Thermal heat dissipation or "stiffness" energy. Same as SENE [1].
KENE Kinetic energy [1].
AENE Artificial energy due to hourglass control/drill stiffness or due to contact stabilization [1].
JHEAT Element Joule heat generation (coupled-field calculation) [1].
JS Source current density for low-frequency magnetic analyses. Total current density (sum of conduction and displacement current densities) in low frequency electric analyses. Components (X, Y, Z) and vector sum (SUM). [1].
JT Total measureable current density in low-frequency electromagnetic analyses. (Conduction current density in a low-frequency electric analysis.) Components (X, Y, Z) and vector sum (SUM). [1].
JC Conduction current density for elements that support conduction current calculation. Components (X, Y, Z) and vector sum (SUM). [1].
MRE Magnetic Reynolds number [1].
VOLU Volume of volume element [1].
CENT Centroid X, Y, or Z location (based on shape function) in the active coordinate system [1].
LOCI Integration point location
SMISCsnumElement summable miscellaneous data value at sequence number snum (Shown in the Output Data section of each element description. See Chapter 4 of the Element Reference) [1].
NMISCsnumElement nonsummable miscellaneous data value at sequence number snum (Shown in the Output Data section of each element description. See Chapter 4 of the Element Reference) [1].
CAPC0,X0,K0,ZONE, DPLS,VPLSMaterial cap plasticity model only: Cohesion; hydrostatic compaction yielding stress; I1 at the transition point at which the shear and compaction envelopes intersect; zone = 0: elastic state, zone = 1: compaction zone, zone = 2: shear zone, zone = 3: expansion zone; effective deviatoric plastic strain; volume plastic strain.
EDPCCSIG,CSTRMaterial EDP creep model only (not including the cap model): equivalent creep stress; equivalent creep strain.
FICTTEMPFictive temperature.
ESIGX,Y,Z,XY,YZ,ZXComponents of Biot’s effective stress.
1, 2, 3Principal stresses of Biot’s effective stress.
INTStress intensity of Biot’s effective stress.
EQVEquivalent stress of Biot’s effective stress.
DPARTPORTotal porosity (Gurson material model).
GPORPorosity due to void growth.
NPORPorosity due to void nucleation.
FFLXX,Y,ZFluid flow flux in poromechanics.
MENE Acoustic potential energy [1].
PMSVVRAT,PPREVoid volume ratio and pore pressure for coupled pore-pressure CPT elements.
FPIDXTF01,SF01, TF02,SF02, TF03,SF03, TF04,SF04Failure plane surface activity status for concrete and joint rock material models: 1 for yielded and 0 for not yielded. Tension and shear failure status are available for all four sets of failure planes.
YSIDXTENS,SHEAYield surface activity status for Mohr-Coloumb, soil, concrete, and joint rock material models: 1 for yielded and 0 for not yielded.

  1. Not supported by PowerGraphics

  2. Works only if failure criteria information is provided. (For more information, see the documentation for the FC and TB commands.)

  3. Some element- and material-type limitations apply. (For more information, see the documentation for the PRERR command.)

  4. Works only if user failure criteria routine is provided.

  5. Do not use the PRESOL command to obtain contact forces for contact elements. The force values reported by this command may not be accurate for these elements. Instead, use the ETABLE command to obtain contact force values.

Menu Paths

Main Menu>General Postproc>List Results>Element Solution
Utility Menu>List>Results>Element Solution

Release 17.0 - © SAS IP, Inc. All rights reserved.